Knowledge · Design

Designing stamped and bent parts

Design for stamping: guidelines for stamped and bent parts from strip covering bend radii, hole diameters, web widths, burr side, rolling direction, tolerances, carrier strip and plated parts. Generally accepted rules of thumb, checked against the production practice of ACA Atlas Contacte GmbH in Wehr (Baden), Germany, a manufacturer of precision stamped and bent parts since 1987.

Contact spring with riveted silver contact, front, plan and side view
Last updated
Reading time
about 10 min
Sections
10
Figures
7

01

Design for stamping: costs are decided on the drawing

A stamped and bent part is a component that is cut and formed from metal strip, in volume production usually in a progressive die or on a stamping and bending machine. Tooling effort, unit price and process reliability depend almost entirely on the geometry shown on the drawing. A tolerance that is too tight, a hole too close to a bend or a bend parallel to the rolling direction can mean an extra die station, rework or scrap.

The following rules are rules of thumb that match our production practice in Wehr. They apply to common materials and thicknesses of contact and spring parts and do not replace a check of the individual part. What is feasible for your part depends on material, temper, geometry and quantity. So talk to us early, ideally before the drawing is released. A short discussion at the concept stage often saves more than any later optimisation.

Stamped copper strip with contact parts at the die exit

02

Rules of thumb at a glance

Rules of thumb at a glance
Criterion Rule of thumb (t = sheet thickness) Reason
Inside bend radius about 1 × t, smaller for soft materials, 2 × t or more for spring tempersRadii that are too small crack on the outside of the bend. The material datasheet gives limits per temper and rolling direction.
Hole diameter at least 1 × t, for stainless steel and spring-temper materials rather 1.5 × tSlender punches buckle or break and wear faster.
Web width and edge distance at least 1 × t, preferably 1.5 × tNarrow webs distort during cutting and tear during bending.
Hole-to-bend distance at least 2 × t plus inside bend radiusCloser holes are distorted by the bend.
Flange length at least 2 to 3 × t plus inside bend radiusFlanges that are too short cannot be guided and bent reliably.
Slot width at least 1 × t, more for hard materialsNarrow slots need thin punches that break easily.
Bend relief width at least 1 × t, depth at least inside bend radius plus tPrevents tearing where a bend line meets an outer edge.

Rules of thumb for orientation at the concept stage, not guaranteed manufacturing limits. We give binding values for your part after reviewing the drawing.

Plan view of a sheet-metal part with two holes, dimensioned with hole diameter d and web width b d b b

Hole, web and edge distance

Rule of thumb

Hole diameter d at least 1 × t, for stainless steel and spring-temper materials rather 1.5 × t. Web width and edge distance b at least 1 × t, preferably 1.5 × t.

Side and plan view of a bend with a hole, dimensioned with the distance a to the bend line a r t

Hole-to-bend distance

Rule of thumb

Distance a at least 2 × t plus the inside bend radius r. A hole any closer is distorted during bending.

Bent part with flange length l and a slot of width w r t l w

Flange length and slot width

Rule of thumb

Flange length l at least 2 to 3 × t plus r. Slot width w at least 1 × t, more for hard materials.

Plan view of a bend relief where the bend line meets the outer edge bend line ≥ t ≥ r + t

Bend relief

Rule of thumb

Width at least 1 × t, depth at least r plus t. Prevents tearing where a bend line meets an outer edge.

Fig. 1 Rules of thumb on the part. The rules of thumb from the table, drawn on a bent sheet-metal part of thickness t. They apply at the concept stage and do not replace a review of the drawing.

03

Bend radius, rolling direction and springback

In bending, the outside is stretched and the inside compressed. If the inside radius is too small, the outer fibre cracks. The permissible minimum radius is usually given as the ratio of radius to thickness and depends on the temper: the harder and springier the temper, the larger the radius must be.

Side view of stations 5 to 8: the spring profile with contact crest and lead-in curl is formed in several steps

Rolled strip has a grain direction. Bend lines across the rolling direction tolerate much smaller radii than bend lines parallel to it. If a part has bends in both directions, it is often placed at an angle in the strip, or the critical direction receives a larger radius. Mark on the drawing which bend is critical to function. We will then align the strip layout accordingly.

After bending, every part springs back slightly. Spring-temper materials and large radii spring back more than soft materials and small radii. The tool compensates for springback by overbending. Tight angle tolerances are possible but need fine-tuning in the tool.

Cross-section of a bend with an inside radius about equal to the sheet thickness t r tension compression neutral axis

Inside radius about 1 × t

Rule of thumb

Rule of thumb for common contact and spring materials. Soft materials also allow smaller radii.

Cross-section of a sharp bend with cracks on the outside t crack

Radius too small

Avoid

The stretched outer fibre cracks.

Cross-section of a bend with a large inside radius for spring-temper materials t r

Spring temper: 2 × t or more

Rule of thumb

The harder and springier the temper, the larger the radius has to be.

Bend angle when overbent in the tool and after springback target angle overbend

Springback

The tool bends beyond the target angle. Once released, the part springs back to the target angle.

Fig. 2 Bend radius and springback. Bending stretches the outside of the bend and compresses the inside. The material datasheet gives binding limits per temper and rolling direction.
Strip section with rolling direction and a bend line across it rolling direction bend line

Bend line across the rolling direction

Recommended

Tolerates much smaller bend radii.

Strip section with rolling direction and a bend line parallel to it rolling direction bend line

Bend line parallel to the rolling direction

Needs a larger radius, otherwise the outside of the bend may crack.

Angled part placed diagonally in the strip, both bend lines at an angle to the rolling direction rolling direction

Bends in both directions

The part is often placed at an angle in the strip, or the critical direction gets a larger radius.

Fig. 3 Bend line and rolling direction. Rolled strip has a grain direction. Mark the bends that are critical to function on the drawing and we will align the strip layout to them.

04

Holes, webs and slots

Holes and cut-outs are cut with a punch and a die plate. The punch cannot be made arbitrarily slender, otherwise it buckles or breaks. That is where the rules of thumb for minimum diameter and slot width come from. Narrow webs between two cut-outs, or between a cut-out and the outer edge, distort during cutting and can tear during bending.

Cutting stations: pilot holes in the carrier, fixing hole, finger slot, notches, embossed dimples and free-cut spring tips

If a hole is too close to a bend line, the bend pulls it oval. If the distance cannot be increased, the hole can be pierced after bending, which usually costs an additional die station. For springs there is a further point: holes, notches and sharp inside corners act as stress raisers in the highly stressed spring zone.

  • Add radii to inside corners rather than leaving them sharp
  • Dimension hole patterns from common datums
  • Keep cut-outs out of the highly stressed spring zone

05

Burr, burr side and cut edge

Every stamped edge has a typical cut surface: a rollover on the side where the punch enters, a smooth burnish zone, a rough fracture zone and, on the exit side, a burr. How high the burr is depends on the cutting clearance, the material and the wear condition of the tool.

The burr side belongs on the drawing. It matters for contact faces, sliding faces, locating faces and safe handling. For bending the rule of thumb is: burr on the inside of the bend wherever possible, because otherwise the stretched outside can crack from the fracture zone. Where a burr is a problem, deburring, coining the edge or reversing the cutting direction can help. Each of these is an additional process step.

Section through punch, sheet and die showing the four zones of the cut edge punch die 1 2 3 4

Zones of the cut edge

1 rollover on the punch side, 2 burnish, 3 fracture zone, 4 burr on the exit side.

Bend with the burr on the inside burr

Burr on the inside of the bend

Recommended

The stretched outside stays clear of the fracture edge.

Bend with the burr on the outside and a crack burr

Burr on the outside of the bend

Avoid

The stretched outside may crack from the fracture zone.

Fig. 4 Cut edge and burr side. Every stamped edge shows the same zones. Burr height depends on the cutting clearance, the material and the wear of the tool.

06

Tolerances: as tight as necessary

Tolerances are among the biggest cost drivers for stamped and bent parts. Cut dimensions produced in a single die station can be held very accurately because the tool reproduces them directly. Dimensions across a bend vary more, because sheet thickness, strength and springback come into play. Dimensions that add up across several bends vary the most.

For untoleranced dimensions, drawings usually refer to a general tolerance standard such as ISO 2768-m. For stamped steel parts, DIN 6930-2 is a dedicated general tolerance standard that takes the specifics of stamping into account. Specify tight tolerances only on functional dimensions, and reference them to the faces on which the part will later locate or make contact.

A common mistake is chain dimensioning across several bends. It is better to dimension from a common datum that is easy to measure on the part. We will tell you which tolerances we can commit to for your part after reviewing the drawing.

Three scatter bands, narrow for cut dimensions, wider across one bend, widest across several bends cut dimension across 1 bend across several bends

Scatter by type of dimension

Cut dimensions from one die station scatter least, dimensions across one bend more, dimensions across several bends most.

Profile with three bends and chained dimensions

Chain dimensioning across several bends

Avoid

The deviations add up from one dimension to the next.

Profile with three bends, all dimensions from a datum face A A

Dimensioning from a common datum

Recommended

Every functional dimension refers to a face that is easy to measure on the part.

Fig. 5 Dimensional scatter and dimensioning. The more bends lie between two faces, the more the dimension scatters. Qualitative illustration without figures.

07

Carrier strip and strip layout

In a progressive die, the part stays connected to the carrier strip until the last station. The strip carries it from station to station. Pilot pins engage pilot holes in the carrier and locate the strip precisely in each station, and the feed equals the pitch in the strip.

Progressive-die strip with carrier and selectively gold-plated contact springs

Three points matter for the design. First, the attachment: where the part is joined to the carrier, a small cut-off stub remains. It should not sit on a contact or sealing face. Second, the position in the strip, which decides rolling direction, material utilisation and bending sequence. Third, the delivery form: if the parts are to be supplied on reels and processed automatically, we agree pitch, carrier width, pilot holes and winding direction with you.

  • Single-sided carrier: compact, good for flat parts
  • Double-sided carrier: stable transport for long or delicate parts
  • Supplied on reel, on tape, in magazines or loose in bulk
Strip with a single-sided carrier, pilot holes and parts at a fixed pitch p pilot hole cut-off point feed p

Single-sided carrier

Compact, good for flat parts.

Strip with a double-sided carrier, pilot holes and parts at a fixed pitch p pilot hole cut-off point feed p

Double-sided carrier

Stable transport for long or delicate parts.

Fig. 6 Carrier strip in the progressive die. The part stays attached to the carrier strip until the last station. Pilot holes locate the strip in every station, and the feed equals the pitch p.

08

Notes on plated parts

With plated parts, the sequence of stamping, bending and plating determines the result. Pre-plated strip is economical but leaves unplated cut edges. If plating takes place after stamping, the edges are protected too, and functional zones can be plated selectively, for example gold on the contact zone and tin on the solder termination.

Brass flat tabs on the carrier strip, solder pins bent and selectively tin-plated

More on layer systems in our guide to materials and finishes and on the surface finishes page.

  • Include layer thicknesses in the tolerance chain, especially for press-fit zones and tight mating dimensions
  • Hard, brittle layers such as nickel or hard gold only tolerate larger radii when bent after plating
  • State functional zones, layer system and minimum thicknesses clearly on the drawing
  • For high-strength steels, consider the risk of hydrogen embrittlement in electroplating
Section through a part made from pre-plated strip with bare cut edges cut edge bare base material

Pre-plated strip

Economical in high volumes. The cut edges stay unplated.

Section through a part plated after stamping with plated edges edge plated base material

Plated after stamping

The edges are plated too, and selective zones are possible.

Contact part with gold on the contact zone and tin on the solder tail contact zone Au solder tail Sn

Selective plating

For example gold on the contact zone and tin on the solder tail.

Fig. 7 Stamping, bending, plating: the order. The order of stamping and plating decides edge protection, formability and cost. The layer build-up of base material, nickel barrier layer and top layer is shown in the guide Materials and finishes.

09

What to include in your enquiry

  • Material and temper

    Material designation with temper and sheet thickness, and for springs the required force-travel characteristic.

  • Finish

    Layer system, thicknesses and functional zones, and whether plating may take place before or after stamping.

  • Functional dimensions

    Functional dimensions with tolerance and datum, burr side and critical bends marked, everything else to general tolerance.

  • Quantity and delivery form

    Annual demand, batch size and the delivery form you need: on reel, on tape, in magazines or loose in bulk.

  • Data

    Drawing as PDF and 3D model, for example as a STEP file. For an existing tool, any information about it is welcome.

  • Inspection requirements

    Special inspection characteristics, first article inspection and the documentation you expect.

10

How we support your design

ACA Atlas Contacte makes stamped and bent parts to drawing and contact springs in its own progressive dies. Send us your draft before the drawing is released.
  1. Consulting

    We check your drawing or concept for manufacturability and suggest changes that make the tool and the unit price more economical.

  2. Design

    If you wish, we design the part with you and define strip layout, carrier strip and bending sequence.

  3. Tool making

    The tool is built in our own tool shop in Wehr. Changes are made there without detours.

  4. Samples and prototypes

    Samples show whether function and tolerances are right before series production starts.

  5. Small batches and series production

    From small batches to high-volume production, in a progressive die or on stamping and bending machines.

FAQ

Frequently asked questions

What bend radius is possible for stamped and bent parts?

As a rule of thumb, an inside bend radius of about one sheet thickness. Soft materials allow smaller radii, spring tempers need two sheet thicknesses or more. Bends across the rolling direction tolerate smaller radii than bends parallel to it. Binding values depend on material and temper and are checked for each part.

How small can a hole in a stamped part be?

As a rule of thumb, the hole diameter should be at least equal to the sheet thickness, and rather 1.5 times the thickness for stainless steel and spring-temper materials. Smaller holes are sometimes possible with special tooling effort but increase tool wear and cost.

Which side should the burr be on in a bent part?

The burr side should always be stated on the drawing. For bends, the burr should be on the inside of the bend wherever possible so that the stretched outside does not crack. For contact, sliding and locating faces, the burr side follows the function.

ISO 2768 or DIN 6930-2: which general tolerance applies to stamped parts?

For stamped steel parts, DIN 6930-2 is a dedicated general tolerance standard that reflects the specifics of stamping. Many drawings refer to ISO 2768-m instead. What matters is that the drawing names one general tolerance clearly and tolerances functional dimensions individually. ACA Atlas Contacte GmbH states the achievable tolerances after reviewing the drawing.

When should the stamping supplier be involved?

As early as possible, ideally before the drawing is released. At the concept stage, radii, hole distances, tolerances and strip layout can still be adjusted without follow-on costs. Once the tool is built, every change costs time and money.

Request a quote

Talk to us early

Send us your drawing while it is still a draft. We check manufacturability, point out critical features and quote for tool and part.